Standard data tables for Hole features
Standard data tables for Hole features
The following standard data tables are provided to set the default parameters for Drill Size Hole, Screw Clearance Hole, Threaded Hole, and Hole Series features:
nx6_Drill_Size_Hole_Standard.xml
nx502_Screw_Clearance_Hole_Standard.xml
nx502_Threaded_Hole_Standard.xml
External standard data table files (that is, lookup tables) provide the best fit default values for holes features. You can choose to bypass the tables and enter all parameters manually.
These tables provide default values for the threads, start chamfer, end chamfer, neck chamfer, and relief chamfer parameters, based on the best fit standard for the selected type of Hole feature.
You can customize these data tables as required. For more information, see Customize standard data tables for Hole features.
Note:
When you customize the standard .xml files, you must retain the column names that define the hole parameters.
A sample standard data table for nx6_Drill_Size_Hole_Standard is shown below:
|
Unit |
Standard |
Size |
Fit |
HoleDiameter |
StartChamferOffset |
StartChamferAngle |
EndChamferOffset |
EndChamferAngle |
|
Metric |
ISO |
0.35 |
Exact |
0.35 |
0.03 |
45 |
0.03 |
45 |
|
Metric |
ISO |
0.38 |
Exact |
0.38 |
0.03 |
45 |
0.03 |
45 |
|
Metric |
ISO |
0.4 |
Exact |
0.4 |
0.03 |
45 |
0.03 |
45 |
|
Metric |
ISO |
0.42 |
Exact |
0.42 |
0.03 |
45 |
0.03 |
45 |
|
Metric |
ISO |
0.45 |
Exact |
0.45 |
0.03 |
45 |
0.03 |
45 |
|
Metric |
ISO |
0.48 |
Exact |
0.48 |
0.03 |
45 |
0.03 |
45 |
This data table is applicable for Screw Clearance Hole and Hole Series type of Hole features.
|
Column name |
Description |
|---|---|
|
Unit |
Specifies the unit used to create the Hole feature. Note: You must ensure that all values in a particular row that define the Hole parameters have the same unit. |
|
Standard |
Specifies the list of standards to be used to create the Hole feature. Lets you specify the standards available in the Standard list under the Settings group in the Hole dialog box. |
|
Form |
Specifies the Form of the Hole feature (Simple, Counterbored, or Countersunk). |
|
ScrewType |
Specifies the screw head types corresponding to the selected standards. |
|
Size |
Specifies the Size of the screw clearance hole. |
|
Fit |
Specifies the Fit of the screw clearance hole (Close, Normal, Loose, or Custom). |
|
ThreadStd ThreadSize ThreadEngage |
Applicable only for End Holes of Threaded form in a Hole Series when the Match Dimensions of Start Hole check box is selected. Specifies the Thread Standard, Size, and Radial Engage options. |
|
Depending on the Standard, Form, Screw Type, Screw Size, and Fit the following columns specify the default values for the corresponding options in the Hole dialog box. You can edit these values directly in the dialog box only when Form is set to Custom. |
|
|
HoleDiameter |
Specifies the value for the Diameter option. |
|
CBoreDia |
Specifies the value for the C-Bore Diameter option. |
|
CBoreDepth |
Specifies the value for the C-Bore Depth option. |
|
CSinkDia |
Specifies the value for the C-Sink Diameter option. |
|
CSinkDepth |
Specifies the value for the C-Sink Depth option. |
|
CSinkReliefDepth |
(For Countersunk holes with a relief). Specifies the value for the Depth option available under Relief in the Form and Dimensions group. |
|
StartChamferOffset |
Specifies the value for the Offset option available under Start Chamfer under Form and Dimensions. |
|
StartChamferAngle |
Specifies the value for the Angle option available under Start Chamfer in the Form and Dimensions group. |
|
NeckChamferOffset |
(For Counterbored holes) Specifies the value for the Offset option available in the Neck Chamfer subgroup under Form and Dimensions. |
|
NeckChamferAngle |
(For Counterbored holes) Specifies the value for the Angle option available under Neck Chamfer in the Form and Dimensions group. |
|
EndChamferOffset |
Specifies the value for the Offset option available under End Chamfer in the Form and Dimensions group. |
|
EndChamferAngle |
Specifies the value for the Angle option available under End Chamfer in the Form and Dimensions group. |
This data table is applicable for Threaded Hole type and End holes in the Hole Series type of Hole features.
|
Column name |
Description |
|---|---|
|
Standard |
Specifies the list of standards to be used to create the Hole feature. Lets you specify the standards available in the Standard list under the Settings group in the Hole dialog box. |
|
Unit |
Specifies the unit used to create the Hole feature. Note: You must ensure that all values in a particular row that define the Hole parameters have the same unit. |
|
Size |
Specifies the Size of the threaded hole feature. |
|
RadialEngage |
Specifies the values for the Radial Engage percentage in the Thread Dimensions group. |
|
MajorDiameter |
Specifies the largest diameter of the thread for the specified standard. |
|
MinorDiameter |
Specifies the smallest diameter of the thread for the specified standard. |
|
TapDrillDiameter |
Specifies the value for the tap drill diameter for the specified standard. |
|
Pitch |
Specifies the distance from a point on a thread to a corresponding point on the next thread, measured parallel to the axis. |
|
Angle |
Specifies the angle included between the sides of the thread measured in a plane through the axis of the threads. |
|
NumStarts |
Specifies whether single or multiple threads should be created. |
|
Tapered |
Set to 0 or 1 to specify whether the thread is tapered. |
|
EndCondition |
Specifies the end condition for threads. |
|
Method |
Defines the thread manufacturing method. For example Rolled, Cut, Ground, and Milled. |
|
ThreadForm |
Determines the thread form to obtain the parameter defaults. For example Trapezoidal, Buttress and so on. |
|
Callout |
References the thread table entry in the .xml files that provide the default values for threads. |
|
Depending on the Standard, Size, and Radial Engage the following columns specify the default values for the corresponding options in the Hole dialog box. You can edit these values directly in the dialog box only when Radial Engage is set to Custom. |
|
|
HoleDepth |
Specifies a value for the hole depth. |
|
ThreadDepth |
Specifies a value for Depth under Form and Dimensions group. |
|
HoleTipAngle |
Specifies value for the tip angle. |
|
ReliefDiameter |
Specifies a value for the Diameter option under Relief in the Form and Dimensions group. |
|
ReliefDepth |
Specifies a value for the Depth option under Relief in the Form and Dimensions group. |
|
ReliefTipAngle |
Specifies a value for the tip angle of the relief. |
|
ReliefChamferAngle |
Specifies a value for the Angle option under Relief Chamfer in the Form and Dimensions group. |
|
ReliefChamferOffset |
Specifies a value for the Offset option under Relief Chamfer in the Form and Dimensions group. |
|
StartChamferDiameter |
Specifies a value for the Diameter option under Start Chamfer in the Form and Dimensions group. |
|
StartChamferAngle |
Specifies a value for the Angle option under Start Chamfer in the Form and Dimensions group. |
|
EndChamferDiameter |
Specifies a value for the Diameter option under End Chamfer in the Form and Dimensions group. |
|
EndChamferAngle |
Specifies a value for the Angle option under End Chamfer in the Form and Dimensions group. |
|
Column name |
Description |
|---|---|
|
Unit |
Specifies the unit used to create the Hole feature. Note: You must ensure that all values in a particular row that define the Hole parameters have the same unit. |
|
Standard |
Specifies the list of standards to be used to create the Hole feature. Lets you specify the standards available in the Standard list in the Settings group. |
|
Size |
Specifies the Size of the drill size hole. |
|
Fit |
Specifies the Fit of the drill size hole feature (Exact or Custom. |
|
Depending on the Standard, Size, and Fit, the following columns specify the default values for the corresponding options in the Hole dialog box. You can edit these values directly in the dialog box only when Form is set to Custom). |
|
|
HoleDiameter |
Specifies the value of the Diameter option under Dimensions in the Form and Dimensions group. |
|
StartChamferOffset |
(For drill size holes) Specifies the default value for the Offset option available under Start Chamfer in the Form and Dimensions group. |
|
StartChamferAngle |
(For drill size holes) Specifies the default value for the Angle option available under Start Chamfer in the Form and Dimensions group. |
|
EndChamferOffset |
(For drill size holes) Specifies the default value for the Offset option available under End Chamfer in the Form and Dimensions group. |
|
EndChamferAngle |
(For drill size holes) Specifies the default value for the Angle option available under End Chamfer in the Form and Dimensions group. |